0  BEGIN PGM 5105_EN MM 
1  ;NC program for milling a keyway into a shaft
2  ;and subsequently deburring this slot at the
3  ;upper edge with a forming tool.
4  ;A standard cycle is programmed for milling this
5  ;slot. For calculating the tool path for
6  ;deburring, an NC program is defined as cycle.
7  ;
8  BLK FORM CYLINDER Y D80 L200 DIST+0
9  ;
10 ;Tool call for milling the slot
11 TOOL CALL "MILL_D6_ROUGH" Z S555
12 ;
13 ;Cycle definition for milling the slot. The shaft
14 ;radius must be defined as coordinate surface.
15 CYCL DEF 253 SLOT MILLING ~
    Q215=+0    ;MACHINING OPERATION ~
    Q218=+63   ;SLOT LENGTH ~
    Q219=+22   ;SLOT WIDTH ~
    Q368=+0.1  ;ALLOWANCE FOR SIDE ~
    Q374=+90   ;ANGLE OF ROTATION ~
    Q367=+0    ;SLOT POSITION ~
    Q207=+500  ;FEED RATE MILLING ~
    Q351=+1    ;CLIMB OR UP-CUT ~
    Q201=-9    ;DEPTH ~
    Q202=+5    ;PLUNGING DEPTH ~
    Q369=+0    ;ALLOWANCE FOR FLOOR ~
    Q206=+150  ;FEED RATE FOR PLNGNG ~
    Q338=+0    ;INFEED FOR FINISHING ~
    Q200=+2    ;SET-UP CLEARANCE ~
    Q203=+40   ;SURFACE COORDINATE ~
    Q204=+50   ;2ND SET-UP CLEARANCE ~
    Q366=+2    ;PLUNGE ~
    Q385=+500  ;FINISHING FEED RATE ~
    Q439=+3    ;FEED RATE REFERENCE
16 ;
17 L  X+0  Y-50  Z+50 R0 FMAX M3 M99 ;Positioning and cycle call
18 ;
19 ;Tool call for deburring
20 ;With the values DL and DR, define the cutting point
21 ;of the tool tooth
22 TOOL CALL "NC_DEBURRING_D8" Z S555 DL-1 DR-3
23 ;
24 ;Definition of the NC program 51051_en.h as cycle
25 SEL CYCLE "51051_en.h"
26 ;
27 ;Parameter input for deburring
28 Q201 = - 1 ;DEPTH
29 Q222 = 80 ;SHAFT DIAMETER
30 Q200 = 2 ;SET-UP CLEARANCE
31 Q204 = 50 ;SECOND SET-UP CLEARANCE
32 Q207 = 300 ;FEED RATE FOR MILLING
33 ;
34 ;You must define the following parameters only
35 ;if further cycles are run between milling the
36 ;slot and deburring.
37 ;Q218 = 63 ;SLOT LENGTH
38 ;Q219 = 22 ;SLOT WIDTH
39 ;Q374 = 90 ;ANGLE OF ROTATION
40 ;Q367 = 0 ;SLOT POSITION
41 ;Q203 = 40 ;COORDINATE SURFACE
42 ;End of parameter input
43 ;
44 L  X+0  Y-50  Z+50 R0 FMAX M99 ;Positioning and cycle call
45 ;
46 M140 MB MAX F9999 ;Retract
47 M30 ;End of program
48 ;
49 END PGM 5105_EN MM